CUTTINGTOOLS / AI
Find equivalents

ISO H — Hardened Steel · H10

H10 — Hardened steel (medium)

Hardness range: 55–60 HRC. Part of the ISO H — Hardened Steel group. Hard turning replaces grinding for many finishing operations on hardened steel above 45 HRC. CBN (cubic boron nitride) and PCBN inserts are required above 55 HRC. Dry machining is preferred — coolant causes thermal shock cracking. Tight radius inserts (rε 0.4–0.8 mm) and low feed rates preserve surface finish.

Machining hardened steel (medium)? Find suitable carbide grades and understand why.

Every maker's AI recommends its own tools. Ours compares all makers and shows the published source behind each answer, or tells you it could not verify.

Picking an operation fills in the question. Edit it before you ask: add the tool type, diameter or hardness.

Material profile — H10

ISO designation
H10 (ISO H — Hardened Steel)
Material
Hardened steel (medium)
Hardness
55–60 HRC
ISO group colour
Hardened Steel

Tooling guidance — H-group

Group summary
CBN/PCBN required above 55 HRC. Dry machining preferred — coolant causes thermal shock.

Insert selection for hardened steel (55–60 HRC) — starting point

ISO application class
H (hardened steel). Above ~45 HRC hard turning replaces grinding; above ~55 HRC CBN / PCBN is required. Match the ISO class across brands (Sandvik, Kennametal, Iscar, Walter, Seco and Mitsubishi) and confirm the CBN grade.
Grade & coating
CBN / PCBN for 55–60 HRC. A honed or chamfered edge prep is essential; carbide will not survive above ~55 HRC.
Geometry
Negative geometry with a T-land or chamfer plus a hone for edge security, and a large nose radius for finish. Very rigid setup. Run dry — coolant causes thermal-shock cracking on CBN.
Starting parameters
CBN Vc ≈ 100–200 m/min, fn ≈ 0.05–0.15 mm/rev, small ap ≈ 0.05–0.25 mm — a finishing regime, dry. Typical starting band — confirm in the advisor or on a sample part.

Selection table: hardened steel (55–60 HRC)

OperationGeometryISO classCoating familyCoolantFirst check
RoughingNot a roughing material at this hardness: small ap, finishing regime onlyHCBN / PCBN; carbide will not survive above about 55 HRCDryCarbide in the holder by mistake: use CBN
FinishingNegative with T-land or chamfer plus hone, large nose radiusHCBN / PCBNDry: coolant causes thermal-shock cracking on CBNEdge replaced on schedule, speed in band
Interrupted cutHoned or chamfered edge prep for edge securityHRobust CBN gradeDryCBN is brittle: minimise interruptions, avoid a too-keen edge
Low rigidity / thin wallNegative with chamfer plus hone; rigid tool and workholdingHCBN / PCBNDrySetup rigidity and overhang before the grade

Check which of your current inserts are covered →

Drilling Hardened steel (medium) with solid carbide: published starting values

These are one manufacturer's published starting values for solid carbide twist drills, read from its catalogue and checked against the source page. Other makers publish different values for their own drills. Pick the row of the drill you actually use; start there, then adjust to your machine, setup rigidity, hole depth and coolant. "Internal coolant ducts" describes the drill's own geometry, not wet or dry machining.

H1.1.2: Hardened steel, hardened and tempered, < 60 HRC (23 drill families)
Drill familyInternal coolant ductsØ 3 mm
Vc / f
Ø 6 mm
Vc / f
Ø 8 mm
Vc / f
Ø 10 mm
Vc / f
Ø 12 mm
Vc / f
Ø 16 mm
Vc / f
Ø 20 mm
Vc / f
Catalogue page
Art. 1946
Solid carbide drills, coating TiAlN
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105434
Art. 2469
coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13406
Art. 2471
Solid carbide drills, coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13407
Art. 2472
Ratio drills without coolant ducts, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105403
Art. 2473
Ratio drills without coolant ducts, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105403
Art. 2474
Solid carbide drills, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105404
Art. 2477
coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13406
Art. 2479
Solid carbide drills, coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13407
Art. 2480
Ratio drills without coolant ducts, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105403
Art. 2719
Solid carbide drills, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105404
Art. 2996
Solid carbide drills, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105404
Art. 4044
coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13408
Art. 4045
coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13408
Art. 5650
RT 100 U Solid carbide drills, coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13407
Art. 5651
Solid carbide drills, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105404
Art. 6023
coating FIRE
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13406
Art. 6026
Ratio drills without coolant ducts, coating FIRE
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105403
Art. 8520
coating Signum
yes35 / 0.0435 / 0.06535 / 0.0835 / 0.09535 / 0.1135 / 0.1435 / 0.165410
Art. 8521
coating Signum
yes35 / 0.0435 / 0.06535 / 0.0835 / 0.09535 / 0.1135 / 0.1435 / 0.165410
Art. 8522
coating Signum
yes35 / 0.0335 / 0.0535 / 0.06535 / 0.07535 / 0.0935 / 0.1135 / 0.13411
Art. 8524
coating Signum
no25 / 0.02525 / 0.0425 / 0.0525 / 0.0625 / 0.0725 / 0.0925 / 0.105405
Art. 8620
coating Signum
yes35 / 0.0435 / 0.06535 / 0.0835 / 0.09535 / 0.1135 / 0.1435 / 0.165410
Art. 8621
coating Signum
yes35 / 0.0435 / 0.06535 / 0.0835 / 0.09535 / 0.1135 / 0.1435 / 0.165410

Vc in m/min, f in mm/rev. Each row is one drill family's own published values; values of different drills are not combined. Article numbers and pages refer to the Gühring general catalogue (cutting data pages 403, 404, 405, 406, 407, 408, 410, 411, 434).

Turn Vc and f into rpm and feed rate →

Milling Hardened steel (medium): published starting values by tool and application

One manufacturer's published starting values for solid milling cutters, read from its catalogue, checked against the page image and linked to the tools whose product pages point to that table. Each table belongs to its own tool family: values of different tools are not combined. Use the row for your tool and your application (slotting, roughing, finishing...), keep within the printed ap and ae, then adjust to your machine and setup.

G-Mold 65 HF (high-feed; catalogue page 705)
Material groupApplicationVc (m/min)ap maxae maxfz Ø 1fz Ø 2fz Ø 3fz Ø 4fz Ø 6fz Ø 8fz Ø 10fz Ø 12fz Ø 16
H1.1.2Slotting175see ap table1xD0.0160.0330.0490.0650.10.130.1850.2250.3
H1.1.2Roughing155see ap table0.3xD0.0240.0490.0730.0950.1450.1950.2450.290.39
H1.1.2(Pre-)Finishing155see ap table0.2xD0.0210.0410.0620.080.1250.1650.2050.2450.33

ap max (mm) by nominal Ø, as printed for this family; pick the row for your material and hardness:

MaterialHardnessØ 1Ø 2Ø 3Ø 4Ø 6Ø 8Ø 10Ø 12Ø 16
Pless than 850 N/mm²0.060.120.180.240.360.480.60.720.96
Pmore than 850 N/mm²0.050.10.150.20.30.40.50.60.8
Mless than 850 N/mm²0.040.080.120.160.240.320.40.480.64
Mmore than 850 N/mm²0.030.070.10.120.180.240.30.360.48
Kless than 240 HB0.060.120.180.240.360.480.60.720.96
Kmore than 240 HB0.050.10.150.20.30.40.50.60.8
STi alloys0.030.070.10.120.180.240.30.360.48
Hless than 55 HRC0.040.080.120.160.240.320.40.480.64
H55-65 HRC0.030.070.10.120.180.240.30.360.48

fz in mm/tooth. ap and ae as printed (xD = times the tool diameter). Tools this table belongs to: High-feed end mills G-Mold 65 HF: Art. 6814, 6830, 6831. Printed correction factors: medium length tools vc -25 % ap -20 % fz -25 %; extra length tools vc -50 % ap -50 % fz -50 %.

G-Mold 55 B, G-Mold 65 B, GA 200 A, GF 200 (ball nose; catalogue pages 706, 707)
Material groupApplicationVc (m/min)ap maxae maxfz Ø 0.5fz Ø 1fz Ø 2fz Ø 3fz Ø 4fz Ø 6fz Ø 8fz Ø 10fz Ø 12
H1.1.2Roughing1750.06xD0.2xD0.0090.0170.0350.0520.070.1050.140.1750.205
H1.1.2(Pre-)Finishing1550.02xD0.05xD0.0090.0170.0350.0520.070.1050.140.1750.205
H1.1.2Fine finishing1550.01xD0.02xD0.0080.0150.030.0450.060.090.120.150.18

fz in mm/tooth. ap and ae as printed (xD = times the tool diameter). Tools this table belongs to: Ball nose end mills G-Mold μ 65 B: Art. 6815, 6816, 6817, 6818, 6819; Ball nose end mills G-Mold 65 B: Art. 6832, 6833, 6834, 6835, 6836; Ball nose end mills G-Mold 55 B: Art. 6844, 6845, 6846, 6847, 6848, 6849; Ball nose end mills GA 200 A: Art. 6984. Printed correction factors: medium length tools vc -25 % fz -25 %; extra length tools vc -50 % fz -50 %; uncoated tools vc -60 % fz -25 %.

G-Mold 55 T, G-Mold 65 T (corner radius / torus; catalogue pages 708, 709)
Material groupApplicationVc (m/min)ap maxae maxfz Ø 0.5fz Ø 1fz Ø 2fz Ø 3fz Ø 4fz Ø 6fz Ø 8fz Ø 10fz Ø 12
H1.1.2Roughing1250.04xD0.3xD0.0060.0130.0250.0380.050.0750.10.1250.15
H1.1.2(Pre-)Finishing1150.03xD0.20xD0.0050.0110.0210.0320.0450.0650.0850.1050.13
H1.1.2Fine finishing1150.01xD0.15xD0.0050.0110.0210.0320.0450.0650.0850.1050.13

fz in mm/tooth. ap and ae as printed (xD = times the tool diameter). Tools this table belongs to: Torus end mills G-Mold μ 65 T: Art. 6820, 6821, 6822, 6823, 6824; Torus end mills G-Mold 65 T: Art. 6837, 6838; Torus end mills G-Mold 55 T: Art. 6850, 6851, 6852, 6853, 6854, 6855. Printed correction factors: medium length tools vc -25 % fz -25 %; extra length tools vc -50 % fz -50 %; uncoated tools vc -60 % fz -25 %.

Turn Vc and fz into rpm and feed rate →

Reaming Hardened steel (medium): published starting values by reamer family

One manufacturer's published starting values for solid carbide and carbide-tipped reamers, read from its catalogue and checked against the page image, each table linked to the reamers whose product pages point to it. Values of different reamer families are not combined. Use the row for your reamer family, then adjust to your machine, stock allowance and setup.

HR 500 (solid carbide; catalogue page 1040)
Material groupVc (m/min)f Ø 2f Ø 3f Ø 4f Ø 6f Ø 8f Ø 10f Ø 12f Ø 14f Ø 16f Ø 20
H1.1.2: Hardened steel, hardened and tempered, < 60 HRC240.050.10.150.250.30.40.40.450.450.5

f in mm/rev. Reamers this table belongs to: Art. 1685, Art. 1686, Art. 1675, Art. 1676.

HR 500 T (solid carbide; catalogue page 1041)
Material groupVc (m/min)f Ø 14f Ø 16f Ø 18f Ø 20f Ø 22f Ø 24f Ø 28f Ø 32f Ø 38f Ø 42
H1.1.2: Hardened steel, hardened and tempered, < 60 HRC240.450.450.50.50.50.550.60.60.650.7

f in mm/rev. Reamers this table belongs to: Art. 1548, Art. 1549.

hardened steel (55–60 HRC): what goes wrong, and what to check first

Edge chipping (CBN is brittle)
Interruptions or too keen an edge chip CBN. Use a honed / chamfered edge, a robust CBN grade, a rigid setup, and minimise interruptions. See the tool-wear guide.
White layer / thermal damage
A worn edge or too-high speed overheats the surface and forms a white layer. Replace edges on schedule and keep speed in band, running dry.
Chatter (rigidity is everything)
In hard turning, chatter is setup, not grade. Shorten overhang and use a rigid tool and workholding.
Rapid wear with the wrong grade
Carbide will not survive above ~55 HRC — use CBN.

Reference data

Frequently asked questions

What insert should I use for hard turning 55–60 HRC steel?

CBN / PCBN with a honed or chamfered edge; carbide will not survive above ~55 HRC. Match the ISO H class across brands and confirm the CBN grade in the advisor.

Can hard turning replace grinding?

For many finishing operations above ~45 HRC, yes — CBN hard turning reaches tight tolerance and good finish with a far more flexible setup, given a rigid machine.

Should I use coolant when hard turning with CBN?

Usually dry — coolant can cause thermal-shock cracking on CBN. Keep the setup rigid and the edge fresh instead.

Why does my CBN edge chip on hardened steel?

CBN is hard but brittle; interruptions or too keen an edge chip it. Use a honed or chamfered edge, a robust grade, and a very rigid setup.

Get cutting parameters for Hardened steel (medium)
The AI advisor maps your specific material condition and operation to a verified insert grade, coating, and Vc/fn range — with live search across the latest tooling catalogs. Edit the question and hit Ask — 3 free answers a day, no account.
Cost check · free · brand-neutral

Are you overpaying on your Hardened steel (medium) inserts? Paste your insert list and get a cost audit in about 30 seconds: cross-brand candidate alternatives at the same ISO application position, and where you are likely overpaying. No signup, no sales call.

Run a free cost audit → Check your whole grade list · free

After the free check: a sourced PDF + XLSX report from about USD 10 (EUR 9) per grade. How buying works

Related materials