A finish callout on a drawing is a number you hit on purpose, not luck. Most of it comes from two levers you already control, feed and nose radius, plus a sharp edge and a setup that does not chatter. Here is what Ra, Rz and RMS actually mean, the typical finish each process can reach, the turning formula that predicts it, and the method to dial in a target. These are reference ranges and standards, not a promise; confirm the verified cutting data for your exact insert with the advisor.
A roughness spec is a parameter and a value. Reading the wrong parameter is the most common way to fail an inspection on a part that was actually fine, so know which one the drawing calls out before you cut.
| Parameter | What it measures | Use it when |
|---|---|---|
| Ra | Arithmetic mean deviation from the mean line, the everyday roughness average | The default callout; good general measure, but it hides single deep scratches |
| Rz | Average maximum peak-to-valley height over several sample lengths | When peaks and valleys matter, sealing faces, fatigue-critical surfaces |
| Rq (RMS) | Root-mean-square roughness, like Ra but weights big deviations more | Often on optical and older US prints; slightly higher than Ra for the same surface |
| N grade | ISO roughness grade number, N1 to N12, mapped to an Ra value | Shorthand on drawings; N6 is Ra 0.8, N8 is Ra 3.2 |
Ra and Rz measure different things, so there is no exact factor between them. A common rough rule is Rz around 4 to 7 times Ra for typical machined profiles, but the real ratio depends on the surface. If the drawing calls out Rz, measure Rz; do not convert from Ra and hope.
These are typical Ra ranges from common practice, not guarantees and not from any one catalog. The finish you get depends on feed, nose radius, edge condition, rigidity and material. Use the band to sanity-check a callout against the process, then confirm with a measurement.
| Process | Typical Ra (µm) | Approx. µin | Notes |
|---|---|---|---|
| Rough turning / milling | 3.2–12.5 | 125–500 | High feed, depth and material removal; finish is not the goal |
| Finish turning / milling | 0.4–3.2 | 16–125 | Light feed, larger nose radius or wiper, sharp edge |
| Drilling | 1.6–6.3 | 63–250 | Bore wall; ream or bore after if a finer finish is needed |
| Reaming | 0.8–3.2 | 32–125 | Sizing and finishing an existing hole |
| Grinding | 0.1–1.6 | 4–63 | Standard route to a fine, controlled finish on hard parts |
| Honing | 0.05–0.4 | 2–16 | Bores, cylinder walls; crosshatch for oil retention |
| Lapping / polishing | 0.012–0.2 | 0.5–8 | Mirror and sealing surfaces; slow and dedicated |
Typical achievable ranges from common production practice. Microinch values are rounded. Subgroup, tooling, rigidity and material shift the result; confirm with a profilometer.
For a turned finish, the ideal roughness left by the tool is mostly geometry: the feed marks the nose radius leaves behind. The standard theoretical relationship is worth knowing because it tells you which lever to pull.
Example: feed 0.1 mm/rev with a 0.8 mm nose radius gives about (0.01 / 25.6) × 1000, roughly 0.39 µm theoretical Ra. The two takeaways from the f² term: halving the feed cuts theoretical roughness to about a quarter, and a bigger nose radius lowers it at the same feed. Real Ra is always rougher than the formula because of edge wear, built-up edge, vibration and material, so treat it as a floor, not a promise.
A larger nose radius or a wiper insert finishes better at a given feed, but it raises radial cutting force and chatter risk on slender or long parts. If the part rings, a smaller nose radius and a stiffer setup can beat a bigger radius that is vibrating. Finish is a system: tool geometry, feed, rigidity and the edge, not a single number.
Change one variable, re-cut, re-measure. A profilometer reading beats eyeballing it, and the chip and wear tell you why the finish moved.
You set the finish with feed and nose radius, but holding it across a run comes down to the right grade and a sharp edge for your material. That is the brand-neutral problem this tool solves: it grounds the grade, geometry and cutting-data recommendation in real catalog data and tells you when there is no verified match, instead of inventing one.
Ra is the arithmetic mean roughness, the average deviation of the surface profile from its mean line, so it smooths over individual peaks and valleys. Rz is the average maximum peak-to-valley height over several sampling lengths, so it is far more sensitive to single deep scratches or tall peaks. Because they measure different things, there is no exact conversion between them. A common rough rule of thumb is Rz roughly 4 to 7 times Ra for a typical machined profile, but the true ratio depends on the surface, so always read the parameter the drawing actually calls out.
As a typical guide, general turning and milling produce about Ra 0.4 to 6.3 micrometres, with careful finish passes reaching the lower end and roughing the higher end. Grinding typically reaches Ra 0.1 to 1.6, honing about 0.05 to 0.4, and lapping or polishing down to a few hundredths of a micrometre. These are typical ranges from common practice, not guarantees. The finish you actually get depends on feed, nose radius, edge condition, rigidity and the material, so confirm it with a measurement.
For a turned finish, theoretical roughness rises with the square of the feed and falls with the nose radius, so the two biggest levers are reducing the feed and increasing the nose radius. Beyond that: use a sharp edge or a dedicated wiper geometry, kill any chatter by shortening the overhang and stiffening the setup, keep cutting speed high enough to avoid built-up edge, and use coolant suited to the material. Change one variable at a time, re-cut and re-measure.
One micrometre equals about 39.37 microinches, so multiply an Ra value in micrometres by 39.37 to get microinches. Common drawing callouts line up as 0.4 micrometres equals about 16 microinches, 0.8 equals about 32, 1.6 equals about 63, and 3.2 equals about 125 microinches. The values are usually rounded to the standard callout on the print.
Free, no strings: 8-brand grade cross-reference (PDF) · ISO material-group cheat-sheet (PDF) · Shop-floor field guide ($12, 16 pages) · All four PDFs bundled ($19, saves $12)
Are you overpaying on your inserts? Paste your insert list and get a cost audit in about 30 seconds: cross-brand equivalents at the same ISO application position, and where you are likely overpaying. No signup, no sales call.